--- title: Flexible PCB Line and Space Limitations to Be Aware Of description: Learn flexible PCB trace width, spacing, via pad, coverlay, and button plating guidelines to improve manufacturability, yield, and reliability. image: https://blog.epectec.com/hubfs/blog/trace-spacing-to-pads.jpg --- [![Epec Engineered Technologies](https://www.epectec.com/images/logo.png "Epec Engineered Technologies")](https://www.epectec.com/) [![Epec Engineered Technologies](https://www.epectec.com/images/logo.png "Epec Engineered Technologies")](https://www.epectec.com/) - [Articles](https://www.epectec.com/articles/) - [Blog](https://blog.epectec.com/) - [Webinars](https://www.epectec.com/webinar/) - [Videos](https://www.epectec.com/videos/) - [Case Studies](https://www.epectec.com/case-studies/) - [News & Events](https://www.epectec.com/news/) - [Customer Portal](https://system.netsuite.com/c.406760/site/NSlogin.html) - [About](https://www.epectec.com/about/overview/) - Back - [Company Overview](https://www.epectec.com/about/overview/) - [Our History](https://www.epectec.com/about/our-history/) - [Culture](https://www.epectec.com/about/culture/) - [Industries Served](https://www.epectec.com/about/industry/) - [Acquisitions](https://www.epectec.com/about/acquisitions.html) - [Operations](https://www.epectec.com/operations/) - Back - [Operational Excellence](https://www.epectec.com/operations/) - [Quality Philosophy](https://www.epectec.com/operations/quality-philosophy.html) - [Quality Assurance Process](https://www.epectec.com/operations/quality-assurance-process.html) - [Global Operations](https://www.epectec.com/operations/global-operations.html) - [Logistics & Supply Chain](https://www.epectec.com/operations/logistics-and-supply-chain.html) - [Inventory Stocking](https://www.epectec.com/operations/inventory-stocking.html) - [Approvals](https://www.epectec.com/operations/approvals.html) - [ITAR Registered](https://www.epectec.com/operations/itar-registered.html) - [Engineering](https://www.epectec.com/engineering/overview/) - Back - [Engineering Overview](https://www.epectec.com/engineering/overview/) - [Engineering Support](https://www.epectec.com/engineering/support/) - [Design Services](https://www.epectec.com/engineering/design-services/) - [EpecDFx™](https://www.epectec.com/engineering/epecdfx/) - [Free DFM File Check](https://www.epectec.com/engineering/free-dfm.html) - [PCB Impedance Calculator](https://www.epectec.com/engineering/impedance-calculator.html) - [Products](https://www.epectec.com/products/) - Back - [Overview](https://www.epectec.com/products/) - [Battery Packs](https://www.epectec.com/batteries/) - [Flex & Rigid-Flex PCBS](https://www.epectec.com/flex/) - [Cable Assemblies](https://www.epectec.com/cable-assemblies/) - [Printed Circuit Boards](https://www.epectec.com/pcb/) - [CNC Machining](https://www.epectec.com/cnc-machining/) - [User Interfaces](https://www.epectec.com/user-interfaces/) - [Flexible Heaters](https://www.epectec.com/flexible-heaters/) - [EC Fans & Motors](https://www.epectec.com/fans-motors/) [Battery Packs![Custom Battery Packs](https://www.epectec.com/images/new-nav/flyout-battery-packs.png "Batteries and Custom Battery Packs")](https://www.epectec.com/batteries/) --- [CNC Machining![CNC Machining](https://www.epectec.com/images/new-nav/flyout-cnc-machining.png "CNC Machining")](https://www.epectec.com/cnc-machining/) [Flex & Rigid-Flex PCBs![Flex and Rigid-Flex Circuits](https://www.epectec.com/images/new-nav/flyout-flex-and-rigid-flex.png "Flex and Rigid-Flex Circuits")](https://www.epectec.com/flex/) --- [User Interfaces![User Interfaces](https://www.epectec.com/images/new-nav/flyout-user-interfaces2.png "User Interfaces Product Solutions")](https://www.epectec.com/user-interfaces/) [Cable Assemblies![Cable Assemblies](https://www.epectec.com/images/new-nav/flyout-cable-assemblies.png "Cable Assemblies")](https://www.epectec.com/cable-assemblies/) --- [Flexible Heaters![Flexible Heaters](https://www.epectec.com/images/new-nav/flyout-flexible-heaters.png "Flexible Heaters")](https://www.epectec.com/flexible-heaters/) [Printed Circuit Boards![Printed Circuit Boards](https://www.epectec.com/images/new-nav/flyout-printed-circuit-boards2.png "Printed Circuit Boards")](https://www.epectec.com/pcb/) --- [EC Fans & Motors![EC Fans and Motors](https://www.epectec.com/images/new-nav/flyout-fans-and-motors.png "EC Fans and Motors")](https://www.epectec.com/fans-motors/) - [Design Guides](https://www.epectec.com/guides/) - [Design Guides](https://www.epectec.com/guides/) - Back - Resources - Back - [Articles](https://www.epectec.com/articles/) - [Blog](https://blog.epectec.com/) - [Webinars](https://www.epectec.com/webinar/) - [Videos](https://www.epectec.com/videos/) - [Case Studies](https://www.epectec.com/case-studies/) - [News & Events](https://www.epectec.com/news/) - [Customer Portal](https://system.netsuite.com/c.406760/site/NSlogin.html) - [Contact Us](https://www.epectec.com/contact/) - Back - [Contact Information](https://www.epectec.com/contact/) - [Our Sales Team](https://www.epectec.com/contact/our-sales-team.html) - [Office Locations](https://www.epectec.com/contact/office-locations.html) - [Career Opportunities](https://www.epectec.com/contact/career-opportunities.html) - [InstantPCB*Quote*™](https://www.epectec.com/instantpcbquote/) - Back - [Overview](https://www.epectec.com/instantpcbquote/) - [Login](https://secure.epecpcb.com/epec/) - [Register](https://secure.epecpcb.com/epec/index2.jsp) [![](https://www.epectec.com/images/InstantPCBQuote-logo.png)](https://www.epectec.com/instantpcbquote/) [Login](https://secure.epecpcb.com/epec/) [Register](https://secure.epecpcb.com/epec/index2.jsp) Register to Quote and Order Your PCBs Fast, Easy & Online, 24/7 - [Home](https://www.epectec.com/) - [Blog](https://blog.epectec.com/) - Flexible PCB Line and Space Limitations to Be Aware Of Share This Page: [LinkedIn](https://blog.epectec.com/#linkedin) [X](https://blog.epectec.com/#x) [Facebook](https://blog.epectec.com/#facebook) [Email](https://blog.epectec.com/#email) # Flexible PCB Line and Space Limitations to Be Aware Of [![Paul Tome](https://blog.epectec.com/hubfs/Blog-Authors/paul-tome.jpg "Paul Tome")](https://blog.epectec.com/author/paul-tome) Written by [Paul Tome](https://blog.epectec.com/author/paul-tome) Posted on May 12, 2021 at 9:30 AM ![Paul Tome](https://blog.epectec.com/hubfs/Blog-Authors/paul-tome.jpg "Paul Tome") - [Tweet](https://twitter.com/share) Many trace width, spacing, and via design rules used in [rigid PCB designs](https://www.epectec.com/pcb/) also apply to [flexible circuits](https://www.epectec.com/flex/). However, flexible materials, coverlay construction, and flex-specific manufacturing processes introduce additional constraints that designers must account for during layout. The flexibility of [polyimide materials](https://blog.epectec.com/differences-between-fr4-and-polyimide-materials-in-flex-circuits), their larger dimensional tolerances, and the specialized plating processes commonly used in flex circuit manufacturing often require larger clearances and more conservative design practices than those used for rigid circuit boards. Understanding these differences early in the design process can help prevent manufacturability issues and improve production yields. [![Check Out Our Free Guide on Rigid-Flex Design Flaws](https://no-cache.hubspot.com/cta/default/707152/ad159ff3-8f69-4b72-b825-e50205bae629.png)](https://cta-redirect.hubspot.com/cta/redirect/707152/ad159ff3-8f69-4b72-b825-e50205bae629) ## Why Flex Circuit Design Rules Differ from Rigid PCBs [Flexible circuit materials](https://www.epectec.com/flex/material-properties.html) behave differently from [rigid PCB laminates](https://www.epectec.com/pcb/laminate-material.html) because they do not contain glass reinforcement. As a result, dimensional tolerances are generally larger and become more significant during etching and throughout manufacturing processes involving heat, pressure, and moisture. **These material characteristics influence:** - Trace widths and spacing - Trace-to-pad clearances - Via sizes and pad dimensions - Coverlay registration requirements - Hole plating processes ![Example of trace widths and spacing](https://blog.epectec.com/hs-fs/hubfs/blog/trace-widths-and-spacing.jpg?width=800&name=trace-widths-and-spacing.jpg) The cumulative effect of these variables often requires greater spacing and larger feature sizes than would be acceptable in a rigid PCB design. ## Trace Width and Spacing Requirements in Flexible Circuits For most areas of a flexible circuit design, trace width and spacing requirements are primarily determined by the base copper thickness being specified. **Standard industry guidelines are as follows:** - **1/3 OZ copper:** 0.003” trace and space - **1/2 OZ copper:** 0.004” trace and space - **1 OZ copper:** 0.005” trace and space - **2 OZ copper:** 0.007” trace and space Copper thicknesses greater than 2 OZ are seldom used in flexible circuit designs because they can significantly reduce [flexibility and bend capability](https://blog.epectec.com/flex-rigid-flex-bend-capabilities). ![Example of trace to adjacent pad spacing.](https://blog.epectec.com/hs-fs/hubfs/blog/trace-spacing-to-pads.jpg?width=800&name=trace-spacing-to-pads.jpg) *Example of trace to adjacent pad spacing.* ## Copper Type Also Affects Flex Performance The [copper used in flex circuits](https://blog.epectec.com/what-is-the-recommended-copper-weight-for-a-flex-pcb) differs from that commonly used in rigid PCB construction. Most flex circuit designs begin with electro-deposited copper that is subsequently processed into rolled annealed copper. This changes the grain structure from a vertical orientation to an elongated horizontal configuration. The resulting material provides greater ductility, making it better suited for applications requiring repeated flexing or enhanced bend reliability. To preserve these mechanical advantages, many flex circuits avoid additional copper plating on external traces during hole plating operations. In these designs, the base copper remains the finished copper thickness. ## Trace-to-Pad Spacing Requirements Trace spacing requirements become more restrictive when traces pass adjacent to external component pads. If the adjacent pad is a via pad, the standard trace and spacing rules based on copper thickness generally apply. Additional clearances become necessary when traces are routed near external SMT or PTH pads because material tolerances and [coverlay or soldermask](https://blog.epectec.com/differences-between-coverlay-and-flexible-solder-mask) requirements must also be considered. ## Designs Using Polyimide Coverlay When [polyimide coverlay](https://blog.epectec.com/what-is-a-flexible-circuit-coverlay) is used, trace-to-pad spacing should typically be increased to a minimum of 0.010". **This larger clearance helps prevent:** - Exposed traces - Coverlay encroachment onto pads - Registration-related manufacturing issues Coverlay material exhibits similar dimensional tolerances to the flex core itself. Additionally, SMT and PTH openings are mechanically created before the coverlay is aligned and laminated to the circuit surface. These openings can further affect coverlay dimensional stability and increase registration tolerances. ## Designs Using Flexible Soldermask Flexible soldermask requires less spacing than coverlay because no separate coverlay alignment process is involved. A typical trace-to-pad spacing of approximately 0.006" can be used when flexible soldermask is applied. ## Hybrid Coverlay and Soldermask Constructions Many [flexible circuit designs](https://www.epectec.com/flex/design/) use a combination of coverlay and soldermask on the same layer. **In this approach:** - Soldermask is used in densely populated component areas where tighter spacing is required. - Coverlay is used throughout the remainder of the circuit to provide protection and durability. This hybrid approach can help balance manufacturability, spacing requirements, and circuit protection. ## Via Hole and Pad Size Requirements Via sizing in flex circuits is influenced by both material dimensional tolerances and the plating processes used during manufacturing. ![Example of via pad size.](https://blog.epectec.com/hs-fs/hubfs/blog/via-hole-pad-size-requirements.jpg?width=800&name=via-hole-pad-size-requirements.jpg) *Example of via pad size.* Undersized via pads are one of the most common manufacturability issues encountered in flexible circuit designs. ## Typical Via Sizes Because flex circuits are generally thinner than rigid PCBs, smaller via holes can often be used. The thinner construction reduces the hole-depth-to-diameter ratio, making hole plating easier to achieve. **Common via sizes include:** - Mechanically drilled 0.008" hole - Mechanically drilled 0.006" hole - Laser-drilled 0.004" hole ### Recommended Via Pad Dimensions **For mechanically drilled vias, the recommended pad oversize is:** - Minimum: +0.010" - Preferred: +0.012" to +0.014" **For example:** - 0.008" drilled hole - 0.018" pad diameter minimum The preferred larger pad dimensions help improve manufacturing yields, particularly in larger circuits where material tolerances can accumulate. For a laser-drilled 0.004" via, the recommended pad oversize is reduced to 0.008". The laser drilling system's optical registration capabilities help compensate for some material variation, allowing for a smaller pad structure. ## Understanding the Selective Pad Plating Process Most flex circuits use a selective pad plating process, also known as button plating. Unlike traditional rigid PCB plating processes, selective pad plating limits copper deposition to: - The plated hole barrel - A small copper ring surrounding the hole Additional copper is not plated across the entire external circuitry surface. ![Cross section of a selective pad plated flex circuit.](https://blog.epectec.com/hs-fs/hubfs/blog/cross-section-of-selective-pad-plated-flex-circuit.jpg?width=800&name=cross-section-of-selective-pad-plated-flex-circuit.jpg) *Cross section of a selective pad plated flex circuit.* **This approach helps maintain:** - The original base copper thickness - The benefits of rolled annealed copper - Circuit flexibility - Mechanical bend reliability - Minimum bend radius capability ## How Button Plating Works A photo-imageable mask is applied to the starting copper surface and processed to expose only the plated-hole locations. The openings created in this masking process are intentionally larger than the hole diameter to accommodate process and material tolerances. As copper plating builds within these openings, a raised copper ring, or button, forms around the hole. The height of this plated button depends on the circuit layer count and required IPC copper thickness. ### For a 2-Layer Design - Minimum copper plating thickness: 0.0005" - Typical button height: 0.0007" to 0.0008" ### For a Design With 3 Layers or More - Minimum copper plating thickness: 0.001" - Typical button height: 0.0012" to 0.0014" ## Why Via Pads Must Be Larger in Selective Pad Plating The raised button structure created during selective pad plating introduces surface topography that directly affects imaging operations. During circuit imaging, the photo-imageable material must conform over the plated button. Adequate flat pad area is required between the plated button and the pad perimeter to maintain proper adhesion. This requirement is one reason for the previously specified minimum 0.010" pad-to-hole oversize. Without sufficient pad area, the photo-imageable material may flake or lose adhesion, significantly reducing manufacturing yields. ## Summary Flexible circuit design rules differ from those used for rigid PCBs because of the materials involved and the manufacturing processes required. While basic trace width and spacing guidelines remain largely dependent on copper thickness, additional considerations such as coverlay registration, trace-to-pad spacing, via pad sizing, and selective pad plating must also be addressed. Understanding how polyimide materials, rolled annealed copper, coverlay construction, and button plating influence manufacturability helps designers establish layouts that better support production yields, flexibility requirements, and long-term mechanical reliability. --- ## Key Takeaways - **Trace Widths and Spacings Depend on Copper Weight:** Flexible PCBs follow similar trace/space rules as rigid PCBs, with minimums ranging from 0.003" (for 1/3 oz copper) to 0.007" (for 2 oz copper). However, heavier copper reduces flexibility and is rarely used beyond 2 oz. - **Coverlay Requires Greater Trace-to-Pad Spacing:** When using polyimide coverlay, trace-to-pad spacing must be increased to at least 0.010" to accommodate material tolerances and mechanical punching. Flexible soldermask allows for tighter spacing, around 0.006", and hybrid coverlay/soldermask approaches are often used. - **Via Pads Must Be Oversized to Ensure Yield:** Flex circuits demand larger via pads than rigid boards to accommodate button plating and material stretch. A typical 0.008" via hole should have a pad at least 0.018", with +0.012" to +0.014" preferred for volume production. - **Selective Pad Plating Improves Flexibility:** The button plating method limits plating to only via barrels and pads, keeping traces at base copper thickness. This enhances flexibility, improves bend reliability, and supports tighter bend radii. - **Laser-Drilled Microvias Allow for Smaller Pads:** Laser-drilled vias (as small as 0.004") offer tighter tolerances due to optical alignment, requiring only 0.008" pad oversize. These are ideal for high-density or space-constrained flex designs. - [Tweet](https://twitter.com/share) Topics: [Flex & Rigid-Flex PCB's](https://blog.epectec.com/topic/flex-rigid-flex-pcbs) --- [Next](https://blog.epectec.com/understanding-how-solder-and-coatings-impact-pcb-shelf-life) | [All posts](https://blog.epectec.com/all) | [Previous](https://blog.epectec.com/circuit-board-solder-mask-what-to-use-and-what-not-to-use) [![New Call-to-action](https://no-cache.hubspot.com/cta/default/707152/4d156df3-b2aa-49a2-b653-d71d26845ec3.png)](https://cta-redirect.hubspot.com/cta/redirect/707152/4d156df3-b2aa-49a2-b653-d71d26845ec3) ## Leave a Comment --- ## Related Posts --- ### Recent Posts --- ### Posts by Topic - [Printed Circuit Boards (161)](https://blog.epectec.com/topic/printed-circuit-boards) - [Product Design (138)](https://blog.epectec.com/topic/product-design) - [Battery Packs (121)](https://blog.epectec.com/topic/battery-packs) - [Cable Assemblies (102)](https://blog.epectec.com/topic/cable-assemblies) - [Flex & Rigid-Flex PCB's (95)](https://blog.epectec.com/topic/flex-rigid-flex-pcbs) - [Electronics Industry (61)](https://blog.epectec.com/topic/electronics-industry) - [User Interfaces (55)](https://blog.epectec.com/topic/user-interfaces) - [Quality Solutions (33)](https://blog.epectec.com/topic/quality-solutions) - [Flexible Heaters (30)](https://blog.epectec.com/topic/flexible-heaters) - [Events, Training, and Support (9)](https://blog.epectec.com/topic/events-training-and-support) - [RF Products (7)](https://blog.epectec.com/topic/rf-products) - [CNC Machining (3)](https://blog.epectec.com/topic/cnc-machining) - [Fans & Motors (1)](https://blog.epectec.com/topic/fans-motors) See All --- --- ### Need Help with A Project? [![Request Design Support](https://blog.epectec.com/hs-fs/hubfs/blog/design-support-ad.jpg?width=350&name=design-support-ad.jpg)](https://info.epectec.com/request-design-support) Our team of engineers are here to help you with all your product needs. [Request Design Support](https://cta-redirect.hubspot.com/cta/redirect/707152/0d3cd574-22cb-48a2-867e-1a7ffba28403) Manufacturing That Eliminates Risk & Improves Reliability [sales@epectec.com](mailto:sales@epectec.com?subject=Website%20Information%20Request) [(888) 995-5171](tel:888-995-5171) ##### Support & Contact Our knowledgeable staff has many years of experience in the industry. We welcome the opportunity to put our skills to work for you! Please contact us with any questions or requests. - [176 Samuel Barnet Blvd, New Bedford, MA](https://maps.app.goo.gl/Q6JVMv3eQgw29fNY8) - [sales@epectec.com](mailto:sales@epectec.com?subject=Website%20Information%20Request) - [(888) 995-5171](tel:888-995-5171) --- ###### Certifications [![UL Certified Manufacturer](https://www.epectec.com/images/certified-ul.png "UL Certified Manufacturer")](http://www.ul.com/) [![ITAR Registered Manufacturer](https://www.epectec.com/images/certified-itar.png "ITAR Registered Manufacturer")](https://www.epectec.com/operations/itar-registered.html) [![RoHS Compliant Manufacturer](https://www.epectec.com/images/certified-rohs-compliant.png "RoHS Compliant Manufacturer")](https://www.epectec.com/pcb/rohs-compliant.html) [![ISO9001 Certified Manufacturer](https://www.epectec.com/images/certified-iso9001.png "ISO9001 Certified Manufacturer")](https://www.epectec.com/operations/approvals.html) [![ISO27001 Certified Manufacturer](https://www.epectec.com/images/certified-iso27001.png "ISO27001 Certified Manufacturer")](https://www.epectec.com/operations/approvals.html) --- - ##### About - [Company Overview](https://www.epectec.com/about/overview/) - [Our History](https://www.epectec.com/about/our-history/) - [Culture](https://www.epectec.com/about/culture/) - [Industries Served](https://www.epectec.com/about/industry/) - [Acquisitions](https://www.epectec.com/about/acquisitions.html) - ##### Operations - [Operational Excellence](https://www.epectec.com/operations/) - [Quality Philosophy](https://www.epectec.com/operations/quality-philosophy.html) - [Quality Assurance Process](https://www.epectec.com/operations/quality-assurance-process.html) - [Global Operations](https://www.epectec.com/operations/global-operations.html) - [Logistics & Supply Chain](https://www.epectec.com/operations/logistics-and-supply-chain.html) - [Inventory Stocking](https://www.epectec.com/operations/inventory-stocking.html) - [Approvals](https://www.epectec.com/operations/approvals.html) - [ITAR Registered](https://www.epectec.com/operations/itar-registered.html) - ##### Engineering - [Engineering Overview](https://www.epectec.com/engineering/overview/) - [Engineering Support](https://www.epectec.com/engineering/support/) - [Design Services](https://www.epectec.com/engineering/design-services/) - [EpecDFx™](https://www.epectec.com/engineering/epecdfx/) - [Free DFM File Check](https://www.epectec.com/engineering/free-dfm.html) - [PCB Impedance Calculator](https://www.epectec.com/engineering/impedance-calculator.html) - ##### Products - [Overview](https://www.epectec.com/products/) - [Battery Packs](https://www.epectec.com/batteries/) - [Flex & Rigid-Flex PCBS](https://www.epectec.com/flex/) - [Cable Assemblies](https://www.epectec.com/cable-assemblies/) - [Printed Circuit Boards](https://www.epectec.com/pcb/) - [CNC Machining](https://www.epectec.com/cnc-machining/) - [User Interfaces](https://www.epectec.com/user-interfaces/) - [Flexible Heaters](https://www.epectec.com/flexible-heaters/) - [EC Fans & Motors](https://www.epectec.com/fans-motors/) ##### Social Community Join our Social Community and keep in touch with all our latest technology investments, current news, upcoming events, and promotions. --- © 2026 Copyright Epec, LLC. All Rights Reserved. [Tariff Resources](https://www.epectec.com/tariff-resources/)|[Privacy Policy](https://www.epectec.com/privacy-policy/)|[Term & Conditions](https://www.epectec.com/terms/site.html)|[Sitemap](https://www.epectec.com/sitemap.html) ```json { "@context" : "https://schema.org", "@type" : "BlogPosting", "author" : { "@type" : "Person", "name" : "Paul Tome", "url" : "https://blog.epectec.com/author/paul-tome" }, "dateModified" : "2026-08-24T18:58:33.206Z", "datePublished" : "2021-05-12T13:30:00.000Z", "headline" : "Flexible PCB Line and Space Limitations to Be Aware Of", "image" : [ "https://blog.epectec.com/hubfs/blog/trace-spacing-to-pads.jpg" ], "mainEntityOfPage" : { "@id" : "https://blog.epectec.com/flexible-pcb-line-and-space-limitations-to-be-aware-of", "@type" : "WebPage" }, "publisher" : { "@type" : "Organization", "logo" : { "@type" : "ImageObject", "url" : "https://blog.epectec.com/hubfs/image/logo.png" }, "name" : "Epec Engineered Technologies" } } ```